PCB Autorouting

Produce a validated Specctra .ses session, or use --routed-board with a real PCB to import the session and publish a separate .kicad_pcb only after native KiCad DRC passes. Verify final-board hashes and surface all warnings. Successful autorouting does not grant fabrication approval.

1. Establish the routing source

Accept either:

• a real, pad-bearing .kicad_pcb updated from the schematic in KiCad; or
• a Specctra .dsn exported by the user from KiCad PCB Editor.

Reject placement review JSON/SVG/HTML and any padless preview/template. Before routing, verify:

• footprints have unique references, physical pads, and named nets;
• the board outline and stackup are final enough for routing;
• footprint positions and orientations have been reviewed;
• net classes, clearances, track widths, and via rules match the selected fab;
• zones are unfilled and obsolete teardrops are removed; and
• critical nets listed below are already routed or deliberately excluded.

2. Run the supported CLI

Use a finite timeout and write an SES:

circuit-weaver autoroute board.kicad_pcb \
  --output board.ses \
  --effort medium \
  --timeout 300

To publish a real PCB after native DRC, add --routed-board final.kicad_pcb. The native KiCad Python bridge exports DSN when the CLI cannot. If neither native Python nor CLI export is available, export DSN in KiCad PCB Editor:

circuit-weaver autoroute board.dsn \
  --output board.ses \
  --effort high \
  --timeout 600

Circuit Weaver probes the installed router before using optional controls. Use only flags advertised by circuit-weaver autoroute --help:

• --effort fast|medium|high selects 100/500/1000 passes.
• --max-passes N overrides the preset; 0 means unlimited.
• --headless is enabled by default; --no-headless opens the GUI.
• --optimization-threads N sets optimizer threads; 0 disables optimization.
• --optimizer-strategy greedy|global|hybrid chooses board-update behavior.
• --optimizer-hybrid-ratio m:n is required only with hybrid.
• --optimizer-item-selection sequential|random|prioritized chooses item order.
• --optimizer-improvement-threshold PERCENT controls optimizer stopping.
• --seed N is accepted only when the installed build advertises -random_seed.
• --freerouting-path PATH selects a launcher/JAR; the environment alternative is CIRCUIT_WEAVER_FREEROUTING.
• --kicad-cli-path PATH selects the capability-probed KiCad CLI.
• --overwrite atomically replaces existing DSN/SES output. Without it, existing output blocks the run.

Do not bypass the wrapper with guessed raw Java flags. Freerouting option names and availability vary by build; the wrapper probes and validates them.

3. Interpret the result truthfully

Treat CLI status and exit code as authoritative:

Status	Exit	Meaning
ok	0	A structurally valid, source-correlated SES was published with zero reported incomplete connections and zero clearance violations.
partial	2	The SES was published, but the router reported incomplete connections. Manual completion is required.
error	1	Preflight, capability, timeout, router, statistics, clearance, DSN/SES validation, or publication failed.

Treat status: partial as unfinished routing even though a diagnostic SES was published; never promote it to success because the file exists.

The wrapper stages output, validates DSN and SES structure, rejects SES nets absent from the source, rejects missing source nets, requires known completion and clearance statistics, and preserves prior output on failure. Do not infer success from a router process exit code or from the mere presence of a file.

4. Import and verify in KiCad

1. Open the same electrical PCB in KiCad PCB Editor.
2. Choose File → Import → Specctra Session and select the published .ses.
3. Confirm the reported net count and any incomplete connections.
4. Refill zones and re-add teardrops only after inspecting the imported routes.
5. Run full KiCad DRC and resolve every violation.
6. Inspect neck-downs, via transitions, acute angles, stubs, return paths, silkscreen, courtyard clearance, and copper-to-edge clearance.
7. Save the verified board as a .kicad_pcb; the SES itself is not the final manufacturing source.

Nets to route manually

Route these before bulk autorouting and review them against the authoritative datasheet/reference layout:

Net class	Reason
Input/output power, planes, and high-current paths	Width, via count, current density, and return path are design constraints.
Buck/boost switch nodes and hot loops	Loop area and parasitics dominate EMI and stability.
Decoupling and bootstrap loops	The shortest physical current path matters more than generic completion.
Differential pairs	Impedance, spacing, skew, and reference-plane continuity require controlled routing.
RF/antenna/matching networks	Vendor geometry, 50-ohm structure, keepouts, and tuning are authoritative.
Crystals and oscillators	Symmetry, parasitics, isolation, and guard strategy are placement-specific.
Clocks, DDR, memory buses, and other timing-critical nets	Topology and length constraints exceed generic autorouting guarantees.
Sensitive analog and feedback nodes	Noise coupling, Kelvin connections, and grounding require engineering judgment.

Completion checklist

• Routing input is a real electrical PCB or valid user-exported DSN.
• Critical nets were routed manually or explicitly excluded.
• Circuit Weaver returned ok, or every partial connection was completed.
• The SES was imported into the matching board in KiCad.
• KiCad DRC is clean after zones are refilled.
• Trace widths, vias, return paths, diff-pair rules, and copper-to-edge rules match the fabrication stackup.
• Final manufacturing exports come from the reviewed .kicad_pcb, not the DSN, SES, or placement review artifacts.